Thanks: 0
Likes: 0
Needs Pictures: 0
Picture(s) thanks: 0
Results 1 to 15 of 80
Thread: Cutting aluminium sheet
-
17th July 2012, 01:40 PM #1
Cutting aluminium sheet
I am having big problems cutting some 3mm thick aluminium panels.
I have tried using 3mm spiral down cut bits cutting at 0.1mm per pass at 160mm per minute. (broke 2 bits at $15 each on this)
I have tried 3mm ball nose bits at the same rate as above. Broke one of these as well when the aluminium fused to the bit and the sheet rode up the bit. But overall I got better results than from the down cut bits
I am currently trying a 6mm spiral down cut, cutting 0.25mm per pass at 600 mm per minute. The bit welded to the sheet again
All these are using the full 24000 rpm of the spindle and I am using kerosene as a lubricant.
These are going to be large panels approx 2.4 metres by 600 mm with lots of detail in the design, so I must be able to just go away and leave the job to finish or alternatively have the job finish in under an hour. Taking such small cuts extends the length of the job considerably.
Does anyone have any ideas on what I am doing wrong?
ThanksBob Willson
The term 'grammar nazi' was invented to make people, who don't know their grammar, feel OK about being uneducated.
-
17th July 2012 01:40 PM # ADSGoogle Adsense Advertisement
- Join Date
- Always
- Location
- Advertising world
- Age
- 2010
- Posts
- Many
-
17th July 2012, 03:56 PM #2
are you cutting all the way through ?
i used plasticine to build dams ( like a good dutchman) and flood the area with synthetic 2 stroke oil , only coz i had some handy (2mm deep ) it helped with my attempt at 3mm plate with a 2mm bit , running at 18000rpm , water might be better than something flammable ?
i was cutting out cogs for a clock , cutting all the way through ( cut2d with tabs ) , so used the machine to mark out the outline with a cut down sharpie and made heeps of small dams , i had problems in the centre of the sheet when vibration caused oil/aluminium sludge to get under the sheet and raised the height
yes i broke 3 bits before i got the feed speed right ( packs of 10 carbides off ebay , 2mm 2 flute bull nose's ) 1/2ing the feed speed each time i broke the bit , i ramped my z down , and 0.1 deep per pass , it was real slow
found i needed degreaser and windex to clean up the aluminium so the plasticine would stick to it if oil had been on the surface ( plastic protective covered aluminium)
also set the bits as deep as possible into the collet , my bits had 12mm cutting depth , when i order another batch i might look for 5 mm high flutes so the collet is closer to the job
i only ever use my spindle to a max of 18000rpm , just my choice ,how come a 10mm peg dont fit in a 10mm hole
-
17th July 2012, 04:33 PM #3GOLD MEMBER
- Join Date
- May 2003
- Location
- Perth WA
- Posts
- 3,784
Hi Bob,
If you want to cut the sheet without breaking bits you are best to stay with an upcut bit 5mm or larger diameter. You are going to need compressed air and your kero and a Whisky as a lubricant.
What is happening is your feed rate is way too slow for 24000 RPM which is causing it to gall up. This in turn fills the flute of your bit with molten ally making it like a solid rod - you can't cut once it does this and the bit breaks. A lot of ally sheet material is gummy and it can vary across a sheet. What you need to do is cut fast enough to make chips and the air will expell those chips from the cut making it a clean cut each pass. Spray your kero around the cut as needed and when using air be careful of blowing chips into your eyes - yeah had it happen on a rebound.
With a 5 or 6mm upcut bit I would recommend 0.5mm DOC and 1200mm/min to start off with. I usually start at this and ramp up the feed rate to around 2m/min. Watch your chips and when you get a "C" shaped chip that is as fast as you need to go. Keep the air and kero going and watch for the sheet lifting during cutting.
The Whisky is for your lubrication as I reckon you will need it by the time you are finished.Cheers,
Rod
-
17th July 2012, 06:44 PM #4
Thanks Ken and Rod
I am cutting all the way through Ken, so although I could use your idea of mini dams all around the cuts, the last few cuts would be problematic. I will also have problems cutting in the centre of the sheet, because the nearest clamps are then 300 mm away, but I am having problems even when they are right next to a clamp, so central cuts would exacerbate the problem no end.
Rod
I could try putting everything back onto a 10 amp circuit so that I can use the 15 amp circuit for the air compressor. The trouble with using upcut bits is when I get towards the middle of the sheet it WILL lift. Maybe I can make up a temporary cross caul to hold the centre down. I did try going a bit faster, but the cutter started making a godawful noise and I chickened out.
So OK; swap over power circuits, fire up compressor, refill kero squirt bottle, use a 6mm up cut bit, 0.5 DOC with 1200 to 2000 mm a minute feed rate with a spindle speed of 20000 and shot glasses lined up along the edge of the table.
That all sounds pretty scary considering what happens at the slower speeds of feed and DOC but I will give it a go tomorrow. (I was looking for a smiley for apprehensiveness to put here)
I was originally intending to make these panels from 6mm aluminium plate. That should'nt take much longer that a couple of days to cut out that eh?Bob Willson
The term 'grammar nazi' was invented to make people, who don't know their grammar, feel OK about being uneducated.
-
17th July 2012, 08:25 PM #5SENIOR MEMBER
- Join Date
- Feb 2008
- Location
- Australia
- Posts
- 988
Can you use double sided tape to hold the aluminium down?
I've seen this work for perspex but I guess it also depends on what your table top is made of, if MDF I don't think it'll stick properly.
-
17th July 2012, 10:15 PM #6Simsy
- Join Date
- Jun 2001
- Location
- Perth, WA (Ellenbrook)
- Age
- 73
- Posts
- 430
Hi Bob
I use 2 flute upcut bits for ally sheet at 0.5mm passes and about 20000rpm. Like Rod, I start out at 1200mm/min feedrate and ramp it up or down depending on the chip size coming off the cutter, and this varies with different types of aluminium. I think using downcut bits would exacerbate your problem by making it difficult for the cutter to clear the chips, so they re-melt and adhere to the cutter. I just use a bit of CRC or WD40 as a lubricant and it works well along with a shot of compressed air every now and then to clear away the swarf. I have used 1/8" cutters as well at 0.3mm and they handle it well too.
Cheers
-
17th July 2012, 11:35 PM #7
Is there any reason you can't cut the sheets using a jig saw and an approprate blade
Ashore
The trouble with life is there's no background music.
-
17th July 2012, 11:55 PM #8GOLD MEMBER
- Join Date
- May 2003
- Location
- Perth WA
- Posts
- 3,784
Bob,
Throw a weight on the ally while it cuts. Lead is good if you have some or a bag of sand will both help to reduce vibration and the sand will spread a long way if you nick it with the cutter.Cheers,
Rod
-
18th July 2012, 12:12 AM #9
Yeah right. I make a machine that costs heaps of money, takes a year to make and is accurate to 0.0005 mm and it should do the job as easy as - so that I can use a jig saw for complicated jobs.
When I first envisaged the project, I actually tried a few samples using a jig saw. It takes ages to cut, is VERY noisy and jig saws are not that accurate. They are also very tiring to use when cutting through 20 or 30 metres of intricate outline.Bob Willson
The term 'grammar nazi' was invented to make people, who don't know their grammar, feel OK about being uneducated.
-
18th July 2012, 12:17 AM #10
Maybe Chris. I hadn't thought of that. It is however an MDF table
Thanks Geoff; noted. I do have some up cut bits so I will try them tomorrow.
Maybe I should get the wife to sit on it. That should hold it down. A good thought though and I will try it out with something, though the only thing I have at present is a bag of rice. Not heavy enough. Thinking, thinking, thinking.Bob Willson
The term 'grammar nazi' was invented to make people, who don't know their grammar, feel OK about being uneducated.
-
18th July 2012, 12:19 AM #11
-
18th July 2012, 02:46 AM #12GOLD MEMBER
- Join Date
- May 2003
- Location
- Perth WA
- Posts
- 3,784
The only way to learn is to make mistakes. I am fast forgetter so sometimes I make them twice.
Cheers,
Rod
-
18th July 2012, 03:58 AM #13
-
18th July 2012, 08:41 AM #14Intermediate Member
- Join Date
- Jan 2009
- Location
- Gundaroo
- Posts
- 41
Hi Bob,
Definitely not an expert but I've had good luck cutting 20mm and 12mm aluminium plate. A proper aluminium endmill for a start (got mine off Drillman on ebay) and its probably counter intuitive but double your speed to 1250mm a minute and drop your router or spindle to 10,000rpm and plenty of kero as lubricant. I put some concreter's plastic down on the bed to protect it from the kero. Hope this helps.
Cheers
Kim
ps. Should have mentioned .5mm per pass with 6mm endmillLast edited by ailmik; 18th July 2012 at 08:44 AM. Reason: Additional stuff added
-
18th July 2012, 10:19 AM #15
Thanks Kim
That confirms what others are saying as well.Bob Willson
The term 'grammar nazi' was invented to make people, who don't know their grammar, feel OK about being uneducated.
Similar Threads
-
Cutting a 90deg into sheet
By vicente in forum WOODWORK - GENERALReplies: 7Last Post: 21st April 2012, 12:14 PM -
CNC router for aluminium and steel sheet?
By elliot42 in forum CNC MachinesReplies: 2Last Post: 23rd January 2011, 11:23 AM -
Cutting Colourbond Sheet.
By STAR in forum METALWORK FORUMReplies: 14Last Post: 11th August 2008, 03:50 PM -
sheet cutting program
By beejay1 in forum WOODWORK - GENERALReplies: 1Last Post: 25th March 2005, 11:10 PM